1526
This is not something we can do for you.
Before starting you will need to have your Racks placed and the machine coordinates for them logged. Machine coordinates can be seen on the F2 Screen.
You can either take a screen shot and view them on a computer or write them down, or log them another way.
After you have your tool locations recorded, go to F1
You'll be prompted for a password, it is either HTG if you bought it from Masso, or there is no password and hit "enter" if you purchased it from Onefinity with your Elite, unless you changed it to something else.
After you are unlocked in the F1 Screen, program Tool Change 1 & 2 as the inputs for Input 7 and 8 and invert the selection by pressing spacebar with it highlighted, and Chuck Clamp M10/M11 as the Output 7. Currently the wire for Output 8 is undesignated and is how you would control the addl' air port on the PE. It is safe to leave it output 8 unassigned, and please visit Masso documentation looking for the logic you'd like to fill the application.
After that select "Tool Changer" on the left, and double click/tap.
A dialog box will pop up. Currently Linear Tool Changer (type 2) is the only one supported.
The next dialog box is where a large portion of time will be spent. All units are native to F1 Screen -> General -> units, and utilize machine coordinates.
Pro tip, hook up a USB keyboard to the Masso unit, either the USB interface on the outside or to the actual unit. You will have to hit backspace for every character you want removed, and Tab works for moving between dialogs, however Shift+Tab does not.
1. The number of slots annotated here is how many predetermined tool rack locations you have.
2. The "Tool change feedrate" is how fast it will move in and out of a tool holder. Rapid speeds will be used in transition from one location to another.
3. Tool holder Z clearance is a machine coordinate for the Z axis and denotes where the Z will move to after it has dropped the tool as it moves to the next tool. At a minimum you need to clear the height of the tools in transition.
4. Pick & Place Location: Regardless of the changer logic, it will need to descend into a position to accept the tool. This is the point in which the spindle will descend to either pick up or place the tool holder in the logic. This is why you cannot mix and match tool holders as there is only 1 height that can be dictated.
5. If you using fork like racks where sliding in and out is necessary this is where you will annotate a drop, slide in, move up, rapid to next tool, pick up the next tool and slide out and continue.
- The numbers in this area are situation dependent, I will annotate using 0, +, - to describe which direction it will go. Video demonstrations here
- Format used: "Tool Clearance Offset 'X'", "Tool Clearance Offset 'Y'" / "Tool Change Offset 'X'", Tool Change Offset 'Y'" (Optimal Placement location)
- 0, 0 / 0, 0 = Down, Place, Up, transition to new tool, Down, Pick, Up, Continue (Anywhere)
- 0, +/ 0, + = Down, Y towards 0, Place, Up, transition to new tool, Down, Pick, Y towards rear, Continue (Along X Axis, Y = 0)
- 0, - / 0, - = Down, Y towards rear, Place, Up, transition to new tool, Down, Pick, Y towards 0, Continue (Along X Axis, Y=Rear)
- +, 0 / +, 0 = Down, X towards 0, Place, Up, transition to new tool, Down, Pick, X towards Right, Continue (X = 0, Along Y)
- -, 0 / -, 0 = Down, X towards Right, Place, Up, transition to new tool, Down, Pick, X towards 0, Continue (X = Right, Along Y)
- -, + / -, + = Down, Diagonal X Right & Y 0, Up transition to new tool, Down, Pick, X towards 0 & Y towards Rear, Continue (X = Right, Along Y, Angled 45 degrees X 0 and Y Rear)
- There is no useful purpose for opposing directions (+, - / -, +) or shared combination of opposite directions.
- Format used: "Tool Clearance Offset 'X'", "Tool Clearance Offset 'Y'" / "Tool Change Offset 'X'", Tool Change Offset 'Y'" (Optimal Placement location)
6. The positions of the tool holders that you either took a screen shot of or transcribed somewhere. All these units are machine coordinates.
Now that you have your tool racks programmed, the only thing left is assign tools to the racks locations.
The F4 tab is where your tool database is located within Masso.
The Tool numbers need to be linked in your CAD software or the ATC Functionality will not work appropriately. You should also have your GCode file saved as one file although its not necessary as you would have to load the next file every time it finishes with the tool path.
1. Is the tool number and this must match what your CAD software is programmed for that tool
2. Slot number is where you would annotate according to the setup where it is located
3. The tool name. Pro-Tip name it in a meaningful way that allows you to identify which bit it is talking about
4. Z-Offset. This is where the tool setter comes in handy. If you haven't already, enable auto tool zero and only auto tool setter when manually requested on the F1 Screen under tool setter
After you double click on a tool, a dialog box will pop up.
1. The tool name populates from the main F4 Screen
2. Z Offset. This is a preloaded offset that masso maintains control of. The Auto Tool Zero button next to it is for getting this calibration height with a tool setter, and is the reason for the "only auto tool setter when manually requested" selection.
3 & 4 Tool Diameter and Tool Dia Wear are both functions that serve no real purpose at this time. Masso has said that they will serve a purpose when v5.100 is released and only active in the beta. Sounds promising as it will modify the gcode as it executes to account for wear. Using a negative number will be the likely way to annotate its being worn.
5. Tool in slot is a drop down where you can select which position according to the settings of the previous page. This does not have to mirror the tool number.
- Manually load tool, a button that shows promise, but it does not have any functionality currently.
- Safe to unclamp, clamp, and unclamp. Irrelevant with the use of the MTC Button we have implemented.
6. Save.
If you have a tool setter and would prefer it touching off after homing and after every tool change. Follow these instructions.
If you would like to only perform touch offs when you command them manually. Follow these instructions
